Design & Tolerancing
Shaft Tolerancing and Fits: Applying ISO Limits and Geometric Controls
An ISO 286-1 H7/g6 fit describes a clearance relationship, not a complete shaft specification. To make a rotating assembly work as intended, the drawing must connect size limits to the features that locate, support, and turn the shaft.
Published November 14, 2026
A fit code is only part of the dimension
In a hole-basis H7/g6 fit, the bore’s lower size limit matches the basic size, while the shaft’s tolerance zone sits below that size. The resulting assembly has clearance at every permitted combination of hole and shaft sizes. That is useful information, but the code does not tell a machinist the basic diameter, identify the shaft’s functional datum, or control how much a bearing seat wobbles as it rotates.
The distinction matters because a shaft is not a single uniform cylinder in service. It may carry bearings, gears, seals, pulleys, and shoulders, each with a different job. A fit defines the dimensional relationship between mating features. Geometric tolerances define relationships such as coaxiality in practice, perpendicularity, and surface runout. A complete drawing uses both kinds of control, chosen around the assembly’s function.
ISO 286-1 establishes the basis of the ISO system of limits and fits; ISO 286-2 provides standard tolerance classes and limit deviations for commonly used nominal sizes. The letter identifies the position of a tolerance zone relative to the basic size, and the number identifies its tolerance grade. Neither is a universal micron value: the actual limits depend on the nominal diameter.
Reading H7/g6 at a real size
Consider a nominal 40 mm shaft running in a 40 mm bore. Under commonly tabulated ISO 286 values for this diameter range, an H7 bore has limits of 40.000 to 40.025 mm. A g6 shaft has limits of approximately 39.975 to 39.991 mm. The clearance therefore ranges from 0.009 mm at the tightest permitted pairing to 0.050 mm at the loosest.
That interval is the fit’s practical meaning. It is not enough to write “H7/g6” by itself: the drawing must show the basic size, such as ⌀40 H7 for the bore and ⌀40 g6 for the shaft, or otherwise make the shared nominal size unambiguous. Confirm the applicable limits in the edition of ISO 286-2 used for the project; published tables, national adoptions, and rounding conventions should be checked before release.
In the hole-basis system, H is a convenient default because standard hole-making tools commonly produce holes at or above the basic size. The shaft’s g zone is below the basic size, creating clearance without requiring an unusually large bore. H7/g6 is often selected for accurate clearance location, but whether it is appropriate depends on load, speed, lubrication, temperature, assembly method, and the accuracy required of the rotating element.
Notice what the code does not promise. It does not guarantee a particular running temperature, lubricant film, noise level, or service life. Nor does it account for coating thickness, thermal expansion, burrs, surface finish, or a shaft seat that is out of round. A nominal fit is a controlled size relationship; it is not a substitute for operating-condition analysis or inspection planning.
Choose the fit from the function
Start by asking what the joint must do. A bearing inner ring may need a tight fit on a shaft if the load rotates relative to the ring and could cause creep. A locating sleeve might need a controlled clearance for adjustment or removal. A gear may require a fit that locates it accurately while a key or spline transmits torque. The same nominal diameter can therefore call for different fits in different places on one shaft.
Fit selection also depends on which component rotates relative to the load. A rotating load on a bearing ring is not equivalent to a stationary load, and the resulting risk of ring creep can influence the recommended interference. Consult the bearing manufacturer’s fit recommendations and the applicable product standards rather than treating a general-purpose shaft fit as a bearing specification.
- Clearance fits allow assembly movement or free rotation; the clearance range must suit guidance, lubrication, and operating conditions.
- Transition fits may produce either slight clearance or slight interference, depending on actual sizes. They can support accurate location when assembly conditions are controlled.
- Interference fits require elastic deformation during assembly and can transmit load without separate locking features, but require checks for assembly stress and resulting distortion.
Temperature can shift the relationship after assembly. If the shaft and hub use different materials, their thermal expansion may differ; even similar materials can reach different temperatures in service. A fit that is satisfactory at room temperature may become tighter or looser in operation. Where that change matters, calculate the operating limits using the expected component temperatures and material properties, then assess the effects on contact pressure, clearance, and stress.
Size tolerance does not control rotation
A shaft can meet its diameter limits and still run poorly. Imagine a bearing seat with the correct average diameter but a centerline that is angled relative to the other bearing seat. The parts may assemble, yet the bearings are misaligned. Or the seat may have acceptable size but vary in radial position as the shaft turns. That variation can affect vibration, seal contact, gear alignment, and bearing loading.
Geometric tolerances address these relationships. ISO 1101 defines the language and framework for geometrical product specifications, including form, orientation, location, and runout. ISO 5459 addresses datums and datum systems. These standards help a drawing state how a feature is controlled relative to other features, rather than merely assigning a size limit to each diameter.
For a shaft, a datum axis is commonly established from one or more functional cylindrical seats, often the bearing journals. Other features—such as a seal seat, gear seat, shoulder, or coupling face—can then be controlled relative to that datum system. The datum should represent how the part is actually located in the assembly. Choosing an arbitrary end face or an easily inspected surface can produce a neat drawing while controlling the wrong relationship.
Datums are not simply labels for surfaces. A datum feature on the part is used to establish a reference during verification; the datum itself is the theoretically exact reference derived from that feature under the specified rules. The drawing’s datum order and any modifiers matter. They influence how the part is set up and which variations are allowed in the functional assembly.
Runout: choose the control that matches the question
Circular runout controls variation at individual circular cross-sections as the part rotates about a datum axis. Total runout applies across the full controlled surface during rotation. For a long bearing seat or seal land, total runout can be useful when the design needs to limit the combined effect of surface variation along the feature, rather than checking one cross-section at a time.
A runout tolerance is meaningful only with a clear datum reference and inspection setup. If the bearing journals establish the shaft’s functional axis, a runout control on a gear seat relative to those journals links the seat to the axis the assembly uses. If the datum references instead rely on an unrelated face or a nonfunctional outside diameter, inspection may certify a relationship that does not reflect how the shaft operates.
Runout is not interchangeable with every other geometric tolerance. It combines aspects of form and location with respect to a datum axis, while a position tolerance addresses the location and orientation of a feature’s derived center or axis under its specified zone. Straightness, cylindricity, and perpendicularity each answer different questions. Use the control that describes the design requirement rather than applying runout as a general “accuracy” symbol.
For example, a shaft drawing might specify a bearing journal’s diameter with an ISO fit designation, then control a gear-mounting diameter’s total runout relative to a datum axis established by the bearing seats. The size requirement determines whether the gear hub can assemble as intended; the runout requirement limits how much the gear seat’s surface departs from the functional rotational axis. Both are necessary if both assembly and running accuracy matter.
A datum-based drawing strategy
Good tolerancing begins with the assembly, not with a collection of familiar symbols. Identify the surfaces that locate the shaft in service, the features that transmit torque, and the surfaces whose motion affects performance. Then decide how those relationships will be manufactured and verified.
- Establish the functional axis. Identify which shaft features locate the rotating assembly—often bearing journals—and choose datum features that reflect that locating method.
- Assign fit classes to mating diameters. Specify a basic size and an ISO tolerance class for each relevant shaft and bore. Avoid copying one fit to every seat without considering its function.
- Control relationships that size limits cannot express. Add suitable runout, orientation, or form requirements where misalignment or surface variation affects operation.
- Define shoulders and axial location. Specify the face relationships, perpendicularity, and axial dimensions needed to seat bearings, spacers, and gears properly.
- Check production and inspection capability. Confirm that the selected tolerances can be manufactured economically and measured with a repeatable method.
A practical drawing review should trace every datum reference to an assembly function. Ask: does this datum reproduce the way the part is supported? Does the geometric tolerance control the feature that drives performance? Can a technician inspect the stated requirement without inventing a setup? If the answer is unclear, the drawing may need a better datum scheme or an explicit inspection note.
Manufacturing and inspection consequences
Tighter limits usually raise cost, but the cost is not confined to machining time. A tight diameter tolerance can require more frequent tool compensation, temperature control, specialized grinding, and measurement equipment. A geometric tolerance may require a precision spindle, a roundness instrument, or a carefully aligned setup. Before tightening a requirement, identify the assembly problem it is intended to prevent.
Measurement method matters. A micrometer can assess local diameter at selected positions, but it does not establish total runout relative to a functional datum axis. A dial indicator setup can reveal runout, but the result depends on how the shaft is supported and how the reference axis is established. Coordinate measuring machines can evaluate complex relationships, but their results still depend on probe strategy, alignment, filtering, and the specified evaluation method.
Surface texture should be considered alongside size and geometry. A journal with compliant diameter limits may still be unsuitable if the surface finish is too rough, has unfavorable lay, or contains defects that disrupt lubrication or damage a seal. Specify surface texture where it is functionally necessary and ensure it is compatible with the manufacturing process. Do not assume that a fit class implies a particular roughness.
Thermal conditions during inspection can also matter at small tolerances. ISO GPS principles, including the default specification operator framework in ISO 8015, help clarify how geometrical product specifications are interpreted. Drawings should identify the governing standards and any project-specific departures. Where a design uses ASME practice, state that basis clearly rather than mixing ISO and ASME conventions without resolving differences in interpretation.
Keep ISO and AGMA references in their lanes
Standards literacy means using the right document for the question. ISO 286 addresses limits and fits; ISO 1101 and ISO 5459 support geometric specification and datum construction. ANSI/AGMA standards address gear design, rating, accuracy, and related gearing topics, depending on the application and selected document. They are not substitutes for the shaft’s fit and datum specification, though gear requirements may impose additional constraints on the shaft and its mounted components.
Likewise, a standard citation should be specific enough to be useful. Give the standard number and edition where the contract or quality system requires it, and verify that the cited edition is current and applicable. A drawing note that says only “per ISO” leaves open which requirements govern. When a customer standard, industry standard, or company specification modifies a general rule, document the hierarchy and the controlling requirement.
For a gear mounted on a shaft, the design team may use an ANSI/AGMA gear standard for gear-related accuracy or rating while specifying the shaft and mating bore using ISO fits. The drawing and technical file should make the interface between these requirements explicit: gear accuracy does not automatically guarantee shaft-seat runout, and shaft diameter limits do not guarantee gear alignment.
Common specification failures
- Writing a fit without a basic size. “H7/g6” is not a complete size callout; show the nominal diameter and identify which component receives each class.
- Using fit class as a runout requirement. Size limits do not establish the axis or constrain a surface’s rotational variation.
- Choosing datums for convenience alone. The reference frame should correspond to the part’s functional location, not merely the easiest surface to touch with a probe.
- Over-tolerancing every seat. Excessive precision can increase cost without improving assembly performance. Apply tighter controls where function demands them.
- Leaving measurement setup implicit. A datum-based requirement needs a repeatable way to establish the datum and evaluate the controlled feature.
- Mixing standards without stating the governing system. ISO and ASME practices can differ in terminology and interpretation; define the applicable basis for the drawing.
The design decision in one sequence
For each shaft feature, first state its job: locate, rotate, support, seal, transmit torque, or establish axial position. Next choose a size fit based on the mating component and operating conditions. Then identify the functional datum system and add geometric controls for the relationships that size limits cannot guarantee. Finally, confirm that manufacturing and inspection can demonstrate compliance.
In the 40 mm H7/g6 example, the fit provides a calculated clearance window of roughly 9 to 50 micrometres under the applicable ISO table values. That is a concrete assembly condition, not proof that a mounted gear will run true or that a bearing will be correctly aligned. A datum-based total runout requirement may address the latter, provided its datum axis represents the assembly’s actual support and the verification method is defined.
That separation—size for assembly, geometry for relationship, and datums for functional reference—turns a fit designation into a usable engineering specification. The result is a drawing that can be manufactured, inspected, and interpreted consistently rather than a collection of symbols that only appears precise.